EMA Academy

Quick How-Tos

Home > EMA Academy > How-Tos > How to Shield RF Signals

How to Shield RF Signals

In many RF applications, shields are required for critical signals to minimize crosstalk and noise. Manually creating shields which follow the structure of the signal trace using dynamic or static shapes and connecting to ground can be a time-consuming process. Shield Routing in Allegro Productivity toolbox generates the desired shielding based on the inputted specifications to quickly shield RF signals and critical nets.

This how-to will provide step-by-step instructions on how to shield RF signal traces during routing and after traces are completed with Allegro Productivity Toolbox and OrCAD PCB Designer.

To follow along with this tutorial, use the provided designs above the table of contents.

How-To Video

5BtHjiN6HyGLeem5AyWHfn

Activating Shield Routing

Step 1: Open the provided design, demo.brd,in OrCAD PCB Designer Professional with the Allegro Productivity Toolbox option selected.

Shielding Step1Note

Note: Allegro Productivity Toolbox can be selected when launching OrCAD PCB Designer. To change licenses, select File > Change Editor.

Shielding Step2
Shield Routing in OrCAD PCB Designer

Step 2: Select Route > Shield Router from the menu.

Configuring Shield Routing Parameters

Shielding Step3
Configuring Options for Shield Routing in OrCAD

Step 3: In the Options tab, under Tandem Shield, set the Width to 3. Leave the default Gap value.

Note: A Tandem Shield will be added on layers above or below the trace.

  • Width: Specifies the amount of oversizing.
  • Gap: Specifies the size of the void inside the shielding. If the values is defined as NA, a gap or void will not be incorporated into the shield.

Step 4: Under Side Shield, set the Width to 2.5. Leave the default Gap value and Style.

Note: A Side Shield will be added on the same layer as the trace.

  • Style: Select from Static Shape, Dynamic Shape, or Route Keepout.

Step 5: Select the ellipsis for the Net. The Select Net window will open.

Shielding Step6
Defining a Ground Net for Shielding

Step 6: Select Gnd from the net list and click OK.

Adding Shields While Routing

Shielding Step7
Shield Traces During Routing with OrCAD

Step 7: In the Options tab, set the mode to Add Connect.

Note: In this mode, shields will be created while routing the signal trace. In this option, the following parameters can be defined:

  • Line Width: Specify the width of the trace.
  • Line Lock: Specify the type of trace as well as the preferred trace angle.
Shielding Step8
Shield RF Signals During Routing

Step 8: Click in the center of connector J6 to begin routing a shielded trace. Click to place the trace.

Shielding Step9

Step 9: About halfway through the routing, right-click and select Toggle.

Note: This reverses the locking sense of the next segment pair being added.

Step 10: Click to complete the routing.

Adding Shielding After Routing

Step 11: In the Options tab, set the mode to Select Clines.

Note: In this mode, the shield structure will be created by selecting existing traces.

Shielding Step12

Step 12: Select the trace that connects J1 and J2. This will add shielding to the trace on its existing path.

Modifying Traces with Shields

Shielding Step13
Sliding Traces in OrCAD

Step 13: Select Route > Slide from the menu or the Slide button on the toolbar.

Shielding Step14
Modifying a Shielded Trace in OrCAD

Step 14: Select a segment of the newly-shielded trace and slide it downwards. Click to place the trace.

Note: The shielding did not move with the trace and must be updated.

Step 15: Select Route > Shield Router from the menu.

Shielding Step16
Updating Trace Shielding in OrCAD

Step 16: In the Options tab, ensure Select Clines is still selected as the mode. Click the trace to update the shielding.

Shielding on Multiple Layers

Shielding Step17
Configuring Advanced Shielding Options

Step 17: Under Parameters, select Advanced.

Step 18: Select the Parameters button. The Shieldroute Advanced Settings window will open.

Shielding Step19
Advanced Shield Routing Parameters in OrCAD

Step 19: Set the Width to 3 and the Gap to 0.8.

Shielding Step20
Adding Shield to Multiple Layers in OrCAD

Step 20: In the Tandem Shielding table below, check the box under Enable for layers L2, L3, and L4.

Note: This will create the shield on multiple layers of the PCB.

Step 21: Still in the Tandem shielding table, set the following Widths:

  • L2 to 3
  • L3 to 4
  • L4 to 5

Step 22: Click OK to save the settings and close the window.

Shielding Step23

Step 23: Select one of the traces connecting J3, J4, and J5.

Step 24: A prompt will appear asking to confirm creation of the shield for a contiguous cline structure. Click Yes to create the shield.

Shielding Step24Note

Note: The shield is created on layers L2, L3, and L4.

Incorporating Vias

Step 25: In the Options tab, under Advanced, select the Parameters button again.

Shielding Step26
Incorporating Vias into Trace Shielding in OrCAD

Step 26: Select the Via Pattern tab at the top of the window.

Note: Some RF applications require additional shielding which can be accomplished by incorporating ground vias into the structure.

Step 27: Under Name table, select Add to add a new via pattern.

Step 28: Enter ring as the name and click OK.

Shielding Step29

Step 29: Select RING from the Name table. Under the Padstacks table, select Add. The Select Via Padstack window opens.

Step 30: Type via* into the search bar and press Enter.

Note: This will search for padstacks that start with “via.”

Shielding Step31

Step 31: Select padstack Via_Tht and click OK.

Step 32: Select the padstack Via_Tht from the Padstacks table.

Shielding Step33

Step 33: Under Parameters, set the Ring Offset to 1.9.

Step 34: Set the Via via gap to 2.0. Leave all other values as the defaults and click OK.

Note: Additional parameters can be configured including:

  • Initial Offset: Specifies the offset for the first via to be generated on the path. The default value is 0 which means the first via will be generated at the starting point of the path. This parameter is useful for tuning purposes when two or more rings need to be generated.

Step 35: Select the trace connecting J8 and J9.

Shielding Step35Note

Note: This will create a shield across multiple layers with connecting vias.

Modifying Existing Shields

Step 36: In the Options tab under Advanced, select Parameters again.

Step 37: In the Tandem Shielding table, deselect the Enable option for L2, L3, and L4. Click OK.

Shielding Step38

Step 38: Select the trace between J8 and J9 again.

Note: The shielding on all other layers has been removed.

Using a Pre-defined Via Pattern

Shielding Step39

Step 39: Close the current demo.brd and open the provided design, demo_share.brd.

Step 40: Select Route > Shield Router from the menu.

Step 41: Select the ellipsis for the Net. The Select Net window will open.

Step 42: Select Gnd from the net list and click OK.

Step 43: In the Parameters section, select Advanced and select the Parameters button.

Step 44: Select the Via Pattern tab at the top of the window.

Shielding Step45
Loading a Pre-defined Via Pattern in OrCAD

Step 45: Select Settings > Load.

Shielding Step46

Step 46: Select the provided file, shield_via_pattern_share.txt, and click Open.

Step 47: Select the padstack Via_Tht from the Padstacks table. Leave the default values and click OK.

Shielding Step48

Step 48: Select the trace connecting J1 and J2.

Step 49: Select the trace connecting J6 and J7.

Step 50: Select the trace connecting J8 and J9.

Modifying a Shielded Trace

Step 51: Select Route > Slide from the menu or the Slide button from the toolbar.

Shielding Step52

Step 52: In the Options tab, select the Bubble drop-down menu and choose Off.

Step 53: Select the trace connecting J1 and J2. Slide the trace upward and click to place.

Shielding Step53Note

Note: The surrounding dynamic copper pour heals itself but the shielding vias do not automatically update.

Updating Trace Shielding

Step 54: Select Route > Shield Router from the menu.

Shielding Step55
Updating Shield Routing in OrCAD

Step 55: In the options tab, set the mode to Update.

Shielding Step56

Step 56: Select the trace connecting J1 and J2.

Step 57: Select the trace connecting J6 and J7.

Note: The shielding vias have been updated.

Wrap Up & Next Steps

Proper shielding for critical nets in RF designs can be time-consuming when using manual methods for shape creation and via placement. Easily define shielding parameters and automatically generate shields and vias following the trace structure with the Shield Router in Allegro Productivity Toolbox. Learn more about the time-saving functionality included in Productivity Toolbox with our free webinar.

Follow Along, Download the Pre-Packaged Design Files

Current Offers

Get access to the latest and greatest CAD tools today.

Table of Contents

How To was created with:
Share:
LinkedIn
Email
EMA Design Automation